 Hey guys, Vladimir here with Desktop Makes. I took a little bit of a hiatus but I am back and glad to be back. I'm going to kick things off with a project I've been wanting to revisit. Back in May of 2017 I had made this automated twist vase kinetic sculpture lamp thing. I wanted to try a different design where the vase twist action still happens but all the mechanics and electronics are hidden in the vase and all you see is this mysterious and hypnotic work of art twisting and moving up and down. It'll look something like this but for real without editing tricks. I'm looking forward to sharing my journey with you and invite you to follow along. In today's video we'll look at designing a small version of the twist vases in Fusion 360. Alright, here's the model we'll be making. You can see our twist vases here and if I grab this and pull it up you can see how it mimics the actual twist of the two containers coming together. So after creating them and probably the next video I'm going to go ahead and show you how we can add the cylindrical joints here in the motion link to make that work. And you know what? We'll also go into motion studies here to set that up. Really cool feature here in Fusion 360 where I can go ahead and just play this as a little preview. Actually let's put that on loop and you can kind of see how that creates that motion. Slow that down a bit. So yeah, we'll cover all of that. Let's just do the designing in this video and then I'll come back with all the cool motion stuff. Alright, we're going to start by creating a new design and we're going to have to approach this with components instead of just some straight up bodies. That's because we're going to add joints and you need components to be able to add joints. So let's dive right in. We'll begin by creating our first component here. I'm going to click right here below our browser where it says unsaved. Since I haven't saved it yet, we're going to name this, we'll start with the inner twist face. I'll just go ahead and call it inner, click OK. And we're going to create a sketch. It will automatically activate that component but if it's not activated you want to make sure that little radial button is clicked. We're going to create a sketch on our XY plane here. I'm going to come in with a polygon, circumscribe polygon. I'm going to position it or the center point right off that origin. I'm going to give it a radius of 25 millimeters and then I'm going to set a horizontal constraint here on that top edge. Finish that sketch and I'm going to come in with another sketch on that front plane there. And here I'm going to grab my line tool, so L for line. I'm going to go straight up 80 millimeters there. Make sure you've got that vertical constraint there, finished sketch. And that is basically it. This is the beauty of these twist faces. They are ridiculously simple to make. I used to make these with the whole different, much more complicated workflow, but this is the way to go here. Alright, so we're going to do our one final step here, which is just to create a sweep. Here we're going to go to create, down to sweep. All we do is select our profiler and then click on path. This line becomes our path. And here we can just give it a twist angle. So if I type 360 or 360 degrees you see our 360 twist. I'm going to back off just slightly and go with 180. And then click OK. Now the reason I just gave me a color there is because I have a component coloring toggled on and that's just a shift N on your keyboard. We'll toggle. We'll just randomly assign colors to your components so you don't have that. Just a gray default look if you want it. Alright, I'm going to click on bodies here. That's on toggle sketches. Don't need to see that. And for 3D printing this, I'm actually going to send this as a solid into the slicer and then I would print it in vase mode. But for just visualization purposes here, I'm going to go ahead and shell this out. And so we'll go to modify shell. I'm going to select the top and the bottom face there and do a 0.5 millimeters. And this will allow us to see how it's going to actually look after it's printed. Alright, that's the first twist face. We're going to come in with our second twist face. I'm going to create a new component for that. So right click new component. I'm going to call this outer. And here I don't need to see that first component. So I'm going to untaggle that visibility there and collapse it. I'm going to begin with the sketch on the XY plane here. And then I'm going to come in with my polygon tool, circumscribe polygon, right under the create menu. I'm going to go with the radius of this time 25.5 because I'm going to leave a half a millimeter gap between the two twist faces there. I'm going to put a horizontal constraint on that top edge there. Finish sketch. And then again, I'm going to come in with a sketch on the front plane here. So that ZX plane, L4 line, I'm going to start right at the origin. I'm going to go straight up, making sure it's straight. I see that vertical constraint. I'm going to give it a distance of 80 millimeters. Finish sketch, create, down to sweep, choose my profile, click path, choose my path, give it a twist angle of 180 degrees, enter. And there we have it. All right, that's our second twist face. How simple was that? Let's just add our shell on this one. So modify shell. I'm just going to shell the bottom here. And this time I want to go with an outside thickness. Otherwise, both bodies will interfere there. So you always have to select the direction first. And then I'm going to do my shell thickness of 0.5 millimeters. Now if I toggle both bodies on by clicking the top level of my component here, make sure both bodies are turned on, I can go into the bottom. If you take a look, and I should have a little gap in between them. And I can inspect that distance by clicking on inspect and clicking both of these edges. And it should tell me 0.5 exactly what I want. And that clearance will control basically how smooth or how fast or slow these twist faces will fall when you drop them and let them go. So you can always play around with that. It's going to differ a little bit for different printers. All right, and that is basically it for designing the twist faces. So you can see here I have a mess component so I can move them around. When you do that, you always want to make sure to click here in a revert position to bring them back. You know what I'm going to do at this stage of actually that inner component there? Let's toggle that. It'll print a lot better if we just give this a base. Looking ahead, the reason I took off the top and bottom is because I might want to fit the whole electronics and other 3D printed parts in here. But at this point, it would make more sense to keep the base there. It'll still work, you would just need a brim if you're going to print this without it. You can have the option of printing it with or without. All you have to do if you go back to the shell command here and timeline, I'm going to edit that. And I hold command and I just click back on that bottom, it'll put the bottom there. But that doesn't matter anyway because when I print this, I'm just going to... I can come here and just suppress that shell feature. So suppress feature and it will just send it as a solid body and then I would use the vase command there or the vase option and the slicer to print it. If you want me to show that, I can show that in a different video but at this video, I just wanted to go ahead and show you how to model these twist vases. Let me go ahead and unsuppress that. So go ahead and make your own, follow along. If you have any questions, leave it in the comments below and I'll gladly check them on them, especially like the first few days after posting this video. If you have a 3D printer, definitely print these out. They're oddly satisfying how they come together and slide within each other. Alright, as always, I will upload the Fusion files, the F3D files, to my Patreon page. As a thank you to all my Patreon supporters and if you're interested in supporting the channel, check the link out below. Also have some links to a few other things including my Fusion 360 constraints, cheat sheets and my online courses. So alright guys, I will see you in a few.